Programming manual

H-2000-6021-0E-A

Inspection software for lathes

for Fanuc 0, 6, 10–15, 16, 18, 21T and iT,

and Yasnac LX3 controllers
© 1998–2013 Renishaw plc. All rights reserved.

This document may not be copied or reproduced in whole or in

part, or transferred to any other media or language, by any means,
without the prior written permission of Renishaw plc.

The publication of material within this document does not imply

freedom from the patent rights of Renishaw plc.

Disclaimer

RENISHAW HAS MADE CONSIDERABLE EFFORTS TO ENSURE

THE CONTENT OF THIS DOCUMENT IS CORRECT AT THE
DATE OF PUBLICATION BUT MAKES NO WARRANTIES OR
REPRESENTATIONS REGARDING THE CONTENT. RENISHAW
EXCLUDES LIABILITY, HOWSOEVER ARISING, FOR ANY
INACCURACIES IN THIS DOCUMENT.

Trade marks

RENISHAW and the probe symbol used in the RENISHAW logo are
registered trade marks of Renishaw plc in the United Kingdom and
other countries. apply innovation and names and designations
of other Renishaw products and technologies are trade marks of
Renishaw plc or its subsidiaries.

All other brand names and product names used in this document
are trade names, trade marks, or registered trade marks of their
respective owners.

Renishaw part no: H-2000-6021-0E-A

Issued: 07.2013
 IMPORTANT – PLEASE READ CAREFULLY

RENISHAW PRODUCT LICENCE

Licensee: you, the person, firm or company accepting the terms of this Licence

Renishaw: Renishaw plc, New Mills, Wotton-under-Edge, Gloucestershire, GL12 8JR, United Kingdom

Product: the software, which is designed to operate on machine tool numeric controllers, supplied by
Renishaw for use with Renishaw’s machine tool probing systems

Licence to use: a non-exclusive licence to use the Product on a single machine tool only

By installing and/or using the Product you indicate your acceptance of the terms of this Licence.

Renishaw grants the Licensee a Licence to use the Product on condition the Licensee accepts the following
terms and conditions:

1. All rights in and title to the Product are and shall remain vested in Renishaw and its licensors.

2. Renishaw shall replace or repair the Product if it does not materially perform to specification under proper use
within 90 days of delivery. This warranty does not apply where the Product has been modified in any manner
that is not specifically described in the Product or in the installation or programming manuals supplied with the
Product, or where the Product is used with probing systems that have not been produced by Renishaw.
Except as stated in this paragraph, all warranties, conditions and terms implied by law are excluded. In
particular, no warranty is given that the Product is bug or error-free.

3. NOTE - LIMITATION OF LIABILITY IN CONNECTION WITH USE OF THE PRODUCT

Renishaw does not exclude liability for personal injury or death caused by Renishaw’s negligence.
Renishaw’s liability is limited to (a) the warranty contained in paragraph 2 and (b) direct losses up to a
maximum of £50,000.
Renishaw has no liability to the Licensee for any indirect, consequential or economic loss (including,
without limitation, loss of data, profits or goodwill).
The Product has been designed for use with Renishaw’s machine tool probing systems. Renishaw has
no liability for the results of using the Product with another manufacturer’s machine tool probing systems.
By accepting the terms of this Licence the Licensee agrees that this limitation of liability is reasonable.

4. The Licensee may not make any copies of the Product except as provided in this Licence or as permitted by
applicable law. The Licensee is authorised to make a backup copy of the Product for security purposes. The
Licensee must not remove any licence and copyright notices, labels or marks contained in the original and shall
ensure all copies contain such notices without modification.

5. If the Product contains electronic manuals the Licensee may print out the manuals in part or in full, provided
that the print outs or copies are not supplied to any third party that is not an employee or contractor for the
Licensee without Renishaw’s written permission

6. The Licensee shall not reverse engineer, decompile, or modify the Product or re-use any components
separately from the Product unless permitted by a specific instruction contained in the Product or the
programming or installation manuals supplied with the Product or by applicable law provided that in the latter
case, Licensee has first contacted Renishaw to request any information required to interface with Licensee’s
other software.

7. The Licensee shall not make the Product available to any third party in any manner whatsoever nor may this
Licence and the Product be transferred to a third party without Renishaw’s prior written agreement. Any
agreement by Renishaw is conditional on the permitted transferee agreeing to all terms of this Licence and the
Licensee not retaining any copies of the Product. Where the Licensee is a reseller of Renishaw’s machine
tool probing systems, Licensee may transfer the Product for ultimate use by an end user with Renishaw’s
machine tool probing systems.

8. Renishaw shall have the right to terminate this Licence immediately if the Licensee fails to comply with any of
these terms and conditions. The Licensee agrees upon receipt of notice of termination from Renishaw to
immediately return or destroy all copies of the Product in its possession or control.

9. This Licence is governed by English law and the parties submit to the exclusive jurisdiction of the English
courts.

Renishaw Product Licence (EN) – Issue 1: February 2007

 Form 1

EQUIPMENT REGISTRATION RECORD

Please complete this form (and Form 2 overleaf if applicable) after the Renishaw equipment has been installed on your machine.
Keep one copy yourself and return a copy to your local Renishaw Customer Support office (see www.renishaw.com/contact for
the address and telephone number). The Renishaw Installation Engineer should normally complete these forms.

MACHINE DETAILS
Machine description ...........................................................................................................................................
Machine type ......................................................................................................................................................
Controller ............................................................................................................................................................
Special control options .......................................................................................................................................
.............................................................................................................................................................................
.............................................................................................................................................................................

RENISHAW HARDWARE RENISHAW SOFTWARE

Inspection probe type ............................................ Inspection disk(s) ...........................................................
Interface type ......................................................... ........................................................................................
........................................................................................
Tool setting probe type .......................................... Tool setting disk(s) ........................................................
Interface type ......................................................... ........................................................................................
........................................................................................

SPECIAL SWITCHING M-CODES (OR OTHER) WHERE APPLICABLE

Dual systems only

Switch (Spin) probe on .......................................... Switch on inspection probe ............................................
Switch (Spin) probe off .......................................... Switch on tool setting probe ..........................................
Start/Error signal .................................................... Other ..............................................................................
........................................................................................

ADDITIONAL INFORMATION Tick box if Form 2 overleaf

has been filled in.

Customer's name ............................................................................ Date installed ........................................

Customer's address .........................................................................
.......................................................................................................... Installation engineer ..............................
..........................................................................................................
.......................................................................................................... Date of training ......................................
Customer's tel. no ............................................................................
Customer's contact name ................................................................
 Form 2

SOFTWARE DEVIATION RECORD

Standard Renishaw kit no. Software disk nos.

Reason for deviation

Software no. and macro no. Comments and corrections

The software product for which these changes are authorised is subject to copyright.

A copy of this deviation sheet will be retained by Renishaw plc.

A copy of the software amendments must be retained by the customer – they cannot be retained by
Renishaw plc.
 Cautions i

Caution – Software safety

!
The software you have purchased is used to control the movements of a machine tool. It
has been designed to cause the machine tool to operate in a specified manner under
operator control, and has been configured for a particular combination of machine tool
hardware and controller.

Renishaw has no control over the exact program configuration of the controller with which
the software is to be used, nor over the mechanical layout of the machine tool. Therefore,
it is the responsibility of the person putting the software into operation to:

 ensure that all machine tool safety guards are in position and working correctly
before commencement of operation;

 ensure that any manual overrides are disabled before commencement of operation;

 verify that the program steps invoked by this software are compatible with the
controller for which they are intended;

 ensure that any moves that the machine tool will be instructed to make under
program control will not cause the machine tool to inflict damage upon itself or upon
any person in the vicinity;

 be thoroughly familiar with the machine tool and its controller, understand the
operation of work co-ordinate systems, tool offsets, program communication
(uploading and downloading) and the location of all emergency stop switches.

IMPORTANT: This software makes use of controller variables in its operation. During its
execution, adjustment of these variables, including those listed within this manual, or of
tool offsets and work offsets, may lead to malfunction.

Publication No. H-2000-6021

ii

This page is intentionally left blank

Publication No. H-2000-6021

 Contents iii

Contents

Before you begin

Before you begin ................................................................................................................. 1
Measurement values used in this manual .......................................................................... 2
Associated publications ...................................................................................................... 2
About the Inspection software ............................................................................................ 2
Software kit no. A-4012-0541 ............................................................................................. 2
File1: Probe horizontal cycles ...................................................................................... 2
File2: Probe vertical cycles .......................................................................................... 3
File3: C-axis cycles ...................................................................................................... 3
Macro memory requirements .............................................................................................. 3
Macro numbers and functions ............................................................................................ 4
Measurement errors............................................................................................................ 5
Renishaw customer services .............................................................................................. 5
Calling Renishaw ......................................................................................................... 5

Chapter 1 Installing the software

Installing the software ...................................................................................................... 1-2
Using the wizard ....................................................................................................... 1-2
Editing macros manually .......................................................................................... 1-2
Setting and adjusting the software................................................................................... 1-2

Chapter 2 Optional inputs

Optional inputs ................................................................................................................. 2-2

Chapter 3 Variable outputs

Table 1 Variable outputs with probe vertical .................................................................... 3-2
Table 2 Variable outputs with probe horizontal ............................................................... 3-2

Chapter 4 Protected positioning cycles

Probe protected positioning (probe vertical) – O9610 ..................................................... 4-2
Probe protected positioning (probe horizontal) – O9810 ................................................. 4-4

Chapter 5 Calibrating the probe

Why calibrate a probe and stylus?................................................................................... 5-2
Single-sided calibration .................................................................................................... 5-2
Double-sided calibration .................................................................................................. 5-3

Publication No. H-2000-6021

iv Contents

Calibrating the probe length............................................................................................. 5-3

Calibration cycles ............................................................................................................. 5-3
Calibrating the probe length (probe vertical) – O9601..................................................... 5-5
Calibrating the stylus Z tool offset double-sided (probe vertical) – O9602 ...................... 5-7
Calibrating the stylus ball radius double-sided (probe vertical) – O9603 ........................ 5-9
Calibrating the stylus single-sided (probe vertical) – O9604 ......................................... 5-11
Calibrating the probe length (probe horizontal) – O9801 .............................................. 5-13
Calibrating the stylus X tool offset double-sided (probe horizontal) – O9802 ............... 5-15
Calibrating the stylus ball radius double-sided (probe horizontal) – O9803 .................. 5-17
Calibrating the stylus single-sided (probe horizontal) – O9804 ..................................... 5-19

Chapter 6 Standard measuring cycles

XZ single surface measurement (probe vertical) – O9611 .............................................. 6-2
Web/pocket measurement (probe vertical) – O9612 ....................................................... 6-5
XZ single surface measurement (probe horizontal) – O9811 .......................................... 6-8
Web/pocket measurement (probe horizontal) – O9812................................................. 6-11

Chapter 7 Additional cycles

Storing multi-stylus data (probe vertical) – O9630 .......................................................... 7-2
Loading multi-stylus data (probe vertical) – O9631 ......................................................... 7-4
Storing multi-stylus data (probe horizontal) – O9830 ...................................................... 7-6
Loading multi-stylus data (probe horizontal) – O9831 ..................................................... 7-8

Chapter 8 C-axis cycles

C-axis find (probe vertical) – O9650 ................................................................................ 8-2
C-axis find (probe horizontal) – O9850 ............................................................................ 8-4

Chapter 9 Alarms and error messages

General alarms ................................................................................................................ 9-2

Chapter 10 Settings, macros and variables

Customising the software .............................................................................................. 10-2
Editing the settings macro (O9524 or O9724) ........................................................ 10-2
Setting #33 .............................................................................................................. 10-3
Variable base number setting (#111 and #112) ..................................................... 10-3
Alarm settings (#110).............................................................................................. 10-3
Process alarms ....................................................................................................... 10-4
Work offset update tests ................................................................................................ 10-4

Publication No. H-2000-6021

 Contents v

Use of macro variables .................................................................................................. 10-4

Local variables ........................................................................................................ 10-4
Common variables .................................................................................................. 10-5
Common retained variables .................................................................................... 10-6

Chapter 11 General information

Tolerances ..................................................................................................................... 11-2
Experience values Ee .................................................................................................... 11-3
Reason for using this option ................................................................................... 11-3
Printing a macro output – an example ........................................................................... 11-3

Appendix A Features, cycles and limitations

Features of the Inspection software................................................................................. A-2
Cycles .............................................................................................................................. A-2
Limitations ........................................................................................................................ A-2

Appendix B Co-ordinate systems used on lathes

Example 1 Tool offset geometry ..................................................................................... B-2
Example 2 Using either G54 to G59 or G50 to define the component zero ................... B-3
G54 to G59 method .................................................................................................. B-3
G50 method setting a program shift to the turret reference position ........................ B-4
Example 3 Using G10 to define the component zero ..................................................... B-5
Example 4 Using either G92 or G50 to define the component zero-to-tool tip
position......................................................................................................................... B-6

Publication No. H-2000-6021

vi Contents

This page is intentionally left blank.

Publication No. H-2000-6021

 Before you begin 1

Before you begin

This programming manual contains detailed information on using the Inspection software
for programming, operating and controlling 2-axis lathes.

Comprising 11 self-contained chapters and two appendices, the manual is structured to

provide the information you require to use the Inspection software effectively.

 Chapter 1, “Installing the software”, describes how to install the Inspection software
on your machine.

 Chapter 2, “Optional inputs”, describes the optional inputs that are required by many
of the cycles.

 Chapter 3, “Variable outputs”, lists the optional outputs that are produced by many
of the cycles.

 Chapter 4, “Protected positioning cycles”, describes how to use the protected

positioning macros (O9610 and O9810). When correctly used, these macros
prevent damage to the stylus in the event of the probe colliding with the workpiece.

 Chapter 5, “Calibrating the probe”, describes how to use the macros that are
provided for calibrating a probe. Cycles are provided for calibrating an inspection
probe when it is vertically mounted and horizontally mounted.

 Chapter 6, “Standard measuring cycles”, describes how to use the non-vector

measuring cycles.

 Chapter 7, “Additional cycles”, describes how to use the four macro cycles that are
not described in previous chapters.

 Chapter 8, “C-axis cycles”, describes how to use two C-axis measuring cycles.

 Chapter 9, “Alarms and error messages”, describes the macro alarm numbers and
messages that are displayed on the screen of the controller when an error occurs.
An explanation of the meaning and possible cause of each alarm message is
provided, together with typical actions you must take to correct the fault causing the
message.

 Chapter 10, “Settings, macros and variables”, describes how to customise the
Inspection software on your machine. It also covers setting information and details
about the macro variables used in the software.

 Chapter 11, “General information”, contains general information and reference

material that is relevant to the Inspection software package.

Publication No. H-2000-6021

2 Before you begin

Measurement values used in this manual

Throughout this manual metric units of measurement (for example, millimetres) are used
in the examples. Where appropriate, the equivalent imperial values (for example, inches)
are shown in brackets.

Associated publications
When you are using the Inspection software, you may find it useful to refer to the following
Renishaw publications:

 Installation manual Probe systems for machine tools (Renishaw part no.
H-2000-6040).

 Data sheets Probe software for machine tools (Renishaw part nos. H-2000-2289
and H-2000-2298).

About the Inspection software

For a comprehensive description of the facilities provided by the Inspection software and
also the limitations of the software, refer to Appendix A, “Features, cycles and limitations”.

Software kit no. A-4012-0541

This kit comprises the following item:

 CD assembly (one CD) – part no. A-4012-0480.

The CD contains the following data:

Probe horizontal cycles File1 (40121191)

Probe vertical cycles File2 (40121192)

C-axis cycles File3 (40121193)

ReadMe (N-4012-1194)

File1: Probe horizontal cycles

O9721 O9724 O9726 O9730 O9732 O9801 O9802
O9803 O9804 O9810 O9811 O9812 O9830 O9831

Publication No. H-2000-6021

 Before you begin 3

File2: Probe vertical cycles

O9521 O9524 O9526 O9530 O9532 O9601 O9602
O9603 O9604 O9610 O9611 O9612 O9630 O9631

File3: C-axis cycles

O9550 O9551 O9650 O9850

Macro memory requirements

This section lists the amount of memory (in kilobytes) that is required by all macros
contained on the software CD. Before you load macros, first calculate the total amount of
memory required by the macros you wish to load. Next, check that the machine controller
has sufficient memory capacity for these macros.

If memory capacity of the controller is stated in “metres of tape”, use the following data to
convert from kilobytes to length or vice-versa:

Conversion: 1 KB = 2.5 m (8.2 ft) of software tape.

8 KB = 20 m (65.6 ft) of software tape.

File1: total amount of memory = 16 KB.

File2: total amount of memory = 16 KB.

File3: total amount of memory = 6 KB.

Publication No. H-2000-6021

4 Before you begin

Macro numbers and functions

Macro No. Function Macro No. Function

File 1 File 2
O9721 X diameter move O9521 Z diameter move
O9724 Settings macro O9524 Settings macro
O9726 XZ basic move O9526 XZ basic move
O9730 Print macro O9530 Print macro
O9732 Offset update macro O9532 Offset update macro
O9801 Probe length calibration O9601 Probe length calibration
O9802 Stylus offset (double-sided O9602 Stylus offset (double-sided
calibration) calibration)
O9803 Stylus ball radius (double- O9603 Stylus ball radius (double-
sided calibration) sided calibration)
O9804 Single-sided calibration O9604 Single-sided calibration
O9810 Protected positioning O9610 Protected positioning
O9811 XZ single surface measure O9611 XZ single surface measure
O9812 Web/pocket measure O9612 Web/pocket measure
O9830 Multi-stylus store O9630 Multi-stylus store
O9831 Multi-stylus load O9631 Multi-stylus load

File 3

O9550 C-axis basic move

O9551 C-axis offset update
O9650 C-axis measure – vertical
O9850 C-axis measure – horizontal

Publication No. H-2000-6021

 Before you begin 5

Measurement errors
When you fit your Renishaw probe into the machine’s shank/holder, the probe’s stylus
may not be in the correct theoretical position. An error may mean the stylus is either
above or below the centre line. Take care to minimise this error otherwise measurements
will be taken across a chord and will not be a true diametral or radial dimension.

The measuring cycles do not mathematically calculate on-centre errors. However, these
errors are usually small, particularly when the probe and stylus have been calibrated on a
diameter that is similar in size to the feature being measured. For a description of how to
calibrate a probe and stylus assembly, see Chapter 5, “Calibrating the probe”.

Renishaw customer services

Calling Renishaw
If you have a question about the software, first consult the documentation and other
information included with your product. If you cannot find a solution, you can receive
information on how to obtain customer support by contacting the Renishaw company that
serves your country (for worldwide contact details, see our main website at
www.renishaw.com/contact).

When you call, it will help the Renishaw support staff if you have the appropriate product
documentation at hand. Please be prepared to provide the following information (as
applicable):

 The version of the product you are using (see the Equipment registration record
form).

 The type of hardware that you are using (see the Equipment registration record
form).

 The exact wording of any messages that appear on your screen.

 A description of what happened and what you were doing when the problem
occurred.

 A description of how you tried to solve the problem.

Publication No. H-2000-6021

6 Before you begin

This page is intentionally left blank

Publication No. H-2000-6021

 Installing the software 1-1

Chapter 1

Installing the software

This chapter describes how to load the Inspection software. It supplements the
information described in the “Software installation” section of the installation manual titled
Probe systems for machine tools (Renishaw part no. H-2000-6040) and the Readme file
on the CD.

Contained in this chapter

Installing the software ...................................................................................................... 1-2
Using the wizard ....................................................................................................... 1-2
Editing macros manually ........................................................................................... 1-2

Setting and adjusting the software ................................................................................... 1-2

Publication No. H-2000-6021

1-2 Installing the software

Installing the software

Using the wizard
The Inspection software is supplied on CD. When the CD is inserted into the CD drive of
the PC, it automatically launches a wizard. The screen displays the following options:

 Programming manual

 Installation manual

 Readme file

 Generate macros

1. Click on Generate macros.

2. Enter appropriate values in the fields. Information is displayed to help you.

3. After you have completed all fields, click the Run button at the bottom of the screen.
The system will generate the macros that are required for your machine set-up. The
macros are stored on your PC in the folder and file that is shown above the Run
button.
The macros can now be loaded into the machine.

Editing macros manually

If, for any reason, the wizard does not work, you will need to edit the macros manually to
suit your machine. Do this as follows:

1. From your PC, explore the CD and locate the folder named Macros.

2. Open the Macros folder and locate a file named Macros.

3. Select the files appropriate to your machine (probe vertical or probe horizontal
and/or C axis) and copy them to your PC.

4. Either edit these files on your PC or load them into your machine and edit them
there.

Setting and adjusting the software

After installing the software, you will need to customise the settings. Chapter 10, “Settings,
macros and variables”, describes general software settings, customising the software,
and how to configure the option settings.

Publication No. H-2000-6021

 Optional inputs 2-1

Chapter 2

Optional inputs

Many of the macros make use of standard optional inputs. Instead of describing them
each time they are required, they are described once in this chapter. You will be referred
to this chapter from other chapters whenever a standard optional input is required.

Details of each non-standard optional input that is required by a macro is provided in the
relevant macro description.

Contained in this chapter

Optional inputs ................................................................................................................. 2-2

Publication No. H-2000-6021

2-2 Optional inputs

Optional inputs
The examples given below assume that the controller has been configured for metric
values (millimetres). The equivalent inch measurement values are shown in brackets.

Ee e= Experience value.
Specify the number of a spare tool offset where an adjustment value to
the measured size is stored (see Chapter 11, “General information”).
Example: E21. causes the experience value stored in tool offset 21 to be
applied to the measured size.

Ff f= This can be either one of the following:

1. The percentage feedback that is used when updating a tool offset
(see Chapter 10, “Settings, macros and variables”).
Enter a value between 0 and 1 (0% and 100%).
Default: 1 (100%).

2. The feedrate that is used in protected positioning macros O9610 and

O9810 (see Chapter 4, “Protected positioning cycles”).
Example: F3000 sets a feedrate of 3000 mm/min.
(F120 sets a feedrate of 120 in/min.)

Hh h= The tolerance value of a feature dimension being measured.

Example: For dimension 50.0 mm +0.4 mm –0 mm, the nominal
tolerance is 50.2 mm with H.2.
(For dimension 1.968 in +0.016 in –0 in, the nominal
tolerance is 1.976 in with H.008.)

Mm m= The true position tolerance of a feature. This is a cylindrical zone about

the theoretical position.
Example: M.1 sets a true position tolerance of 0.1 mm.
(M.004 sets a true position tolerance of 0.004 in.)

Qq q= This is the probe overtravel distance for use when the default values are
unsuitable. The probe will then travel beyond the expected position when
it searches for a surface.
Default: 4 mm (0.16 in) in the Z axis
10 mm (0.394 in) in the X axis.
Example: Q8. sets an overtravel distance of 8 mm.
(Q.3 sets an overtravel distance of 0.3 in.)

Publication No. H-2000-6021

 Optional inputs 2-3

Rr r= This is an incremental dimension that is used on external features, such

as bosses and webs, to give a radial clearance from the nominal target
surface prior to a Z-axis move.
Default: 5 mm (0.200 in).
Example: R10. sets a radial clearance of 10 mm.
(R.4 sets a radial clearance of 0.4 in.)

R–r –r = This is similar to Rr, except that the clearance is applied in the opposite
direction to force an internal boss or web cycle.
Default: 5 mm (0.200 in).
Example: R–10.sets a radial clearance of –10 mm.
(R–.4 sets a radial clearance of –0.4 in.)

Ss s= The number of the work offset to be updated.

S0 The external work offset.
S1 to S6 G54 to G59.
S7 Update G10P0XZ.
S8 The incremental G50W- - move will be active until another
G50 is read.
Example: S3 will set G56

Tt t= The tool offset that is to be updated.

T<1000 The X wear or Z wear will be updated.
T>1000 The radius wear of a milling tool will be updated.
Example: T1 = update the X-wear or Z-wear compensation.
T1001 = update the R-wear compensation.

Uu u= Upper tolerance limit.

If this value is exceeded, no tool offset or work offset is updated and the
cycle stops with an alarm. Where applicable, this tolerance applies to both
size and position.
Example: U2. to set the upper tolerance limit to 2 mm.
(U.08 to set the upper tolerance limit to 0.08 in.)

Vv v= Null band.
This is the tolerance zone where no tool offset adjustment occurs.
Default: 0.
Example: V.5 for a tolerance zone of ±0.5 mm.
(V.02 for a tolerance zone of ±0.02 in.)

Publication No. H-2000-6021

2-4 Optional inputs

Ww w= Print the output data.

W1. Increment the feature number only.
W2. Increment the component number and reset the feature number.
Example: W1.

Publication No. H-2000-6021

 Variable outputs 3-1

Chapter 3

Variable outputs

This chapter lists the variable outputs that may be produced by some of the macros. You
will be referred to this chapter from other chapters when a variable output is produced.

Contained in this chapter

Table 1 Variable outputs with probe vertical .................................................................... 3-2

Table 2 Variable outputs with probe horizontal ................................................................ 3-2

Publication No. H-2000-6021

3-2 Variable outputs

Table 1 Variable outputs with probe vertical

Single surface Web/pocket diameter C-axis measure
G65P9611 G65P9612 G65P9650
#135 X position X position
#137 Z position Z position
#138 Size Size
#139 C position
#140 X error X error
#142 Z error Z error
#143 Size error Size error
#144 C error
#145 True position error True position error
#146 Metal condition Metal condition
#147 Direction indicator Direction indicator
#148 Out of tolerance flag
#149 Probe error flag

Table 2 Variable outputs with probe horizontal

Single surface Web/pocket diameter C-axis measure
G65P9811 G65P9812 G65P9850
#135 X position X position
#137 Z position Z position
#138 Size Size
#139 C position
#140 X error X error
#142 Z error Z error
#143 Size error Size error
#144 C error
#145 True position error True position error
#146 Metal condition Metal condition
#147 Direction indicator Direction indicator
#148 Out of tolerance flag
#149 Probe error flag

Publication No. H-2000-6021

 Protected positioning cycles 4-1

Chapter 4

Protected positioning cycles

As the probe moves around the workpiece it is important that the stylus is protected
against a collision with the workpiece. This chapter describes how to use the protected
positioning cycles. After they are set correctly, the probe will stop moving in the event of a
collision.

Contained in this chapter

Probe protected positioning (probe vertical) – O9610 ..................................................... 4-2

Probe protected positioning (probe horizontal) – O9810 ................................................. 4-4

Publication No. H-2000-6021

4-2 Protected positioning cycles (probe vertical)

Probe protected positioning (probe vertical) – O9610

Figure 4.1 Probe protected positioning (probe vertical)

Description
It is important to protect the probe’s stylus against damage should it collide with an
obstacle as the probe moves around the workpiece. When this cycle is used, the machine
will stop in the event of a collision.

Application
The probe is selected and moved to a safe plane. At this point the probe is made active. It
then moves to a measuring position using this macro call.

In the event of a collision the machine will stop. Either a PATH OBSTRUCTED alarm is
generated or error flag #148 is set (see the Mm input).

Format
G65 P9610 Xx and/or Zz [ Ff Mm ]
where [ ] denote optional inputs.

Example: G65 P9610 Z10. F3000. M1.

Publication No. H-2000-6021

 Protected positioning cycles (probe vertical) 4-3

Compulsory inputs
Xx x= The target diameter position for the probe positioning move.

and/or

Zz z= The target position for the probe positioning move.

Optional inputs
Ff f= The modal feedrate for all protected positioning moves.
The feedrate will be modal to this macro and subsequent feedrate
calls are unnecessary unless a change of feedrate is required. The
maximum safe fast feedrate established during installation must not
be exceeded.

M1. This will set a probe trigger flag (but with no PATH OBSTRUCTED
alarm).
#148 = 0 No probe trigger.
#148 = 7 Probe triggered.

Example
Proprietary G and M codes.

T??? Select the probe.

M?? Switch on the probe.

G65P9610Z-10.X30.F3000 Protected positioning move.

G65P9611X20.T3. Single surface measure.

M?? Switch off the probe.

Publication No. H-2000-6021

4-4 Protected positioning cycles (probe horizontal)

Probe protected positioning (probe horizontal) – O9810

Figure 4.2 Probe protected positioning (probe horizontal)

Description
It is important to protect the probe’s stylus against damage should it collide with an
obstacle as the probe moves around the workpiece. When this cycle is used, the machine
will stop in the event of a collision.

Application
The probe is selected and moved to a safe plane. At this point the probe is made active. It
then moves to a measuring position using this macro call.

In the event of a collision, the machine will stop. Either a PATH OBSTRUCTED alarm is
generated or error flag #148 is set (see the Mm input).

Format
G65 P9810 Xx and/or Zz [ Ff Mm ]
where [ ] denote optional inputs.

Example: G65 P9810 Z10. F3000. M1.

Compulsory inputs
Xx x= The target diameter position for the probe positioning move.

and/or

Zz z= The target position for the probe positioning move.

Publication No. H-2000-6021

 Protected positioning cycles (probe horizontal) 4-5

Optional inputs
Ff f= The modal feedrate for all protected positioning moves.
The feedrate will be modal to this macro and subsequent feedrate
calls are unnecessary unless a change of feedrate is required. The
maximum safe fast feedrate established during installation must not
be exceeded.

M1. This will set a probe trigger flag (but with no PATH OBSTRUCTED
alarm).
#148 = 0 No probe trigger.
#148 = 7 Probe triggered.

Example
Proprietary G and M codes.

T??? Select the probe.

M?? Switch on the probe.

G65P9810X30.Z-10.F3000 Protected positioning move.

G65P9811X20.T8 Single surface measure.

M?? Switch off the probe.

Publication No. H-2000-6021

4-6 Protected positioning cycles (probe horizontal)

This page is intentionally left blank.

Publication No. H-2000-6021

 Calibrating the probe 5-1

Chapter 5

Calibrating the probe

Before a probe and stylus are used, they must be calibrated correctly. Only when they
have been calibrated accurately can you achieve total quality control over your
manufacturing process.

This chapter explains why it is so important that the probe and stylus are calibrated and
then describes how to use the macros that are provided to calibrate them.

Contained in this chapter

Why calibrate a probe and stylus?................................................................................... 5-2

Single-sided calibration .................................................................................................... 5-2

Double-sided calibration .................................................................................................. 5-3

Calibrating the probe length............................................................................................. 5-3

Calibration cycles ............................................................................................................. 5-3

Calibrating the probe length (probe vertical) – O9601..................................................... 5-5

Calibrating the stylus Z tool offset double-sided (probe vertical) – O9602 ...................... 5-7

Calibrating the stylus ball radius double-sided (probe vertical) – O9603 ........................ 5-9

Calibrating the stylus single-sided (probe vertical) – O9604 ......................................... 5-11

Calibrating the probe length (probe horizontal) – O9801 .............................................. 5-13

Calibrating the stylus X tool offset double-sided (probe horizontal) – O9802 ............... 5-15

Calibrating the stylus ball radius double-sided (probe horizontal) – O9803 .................. 5-17

Calibrating the stylus single-sided (probe horizontal) – O9804 ..................................... 5-19

Publication No. H-2000-6021

5-2 Calibrating the probe

Why calibrate a probe and stylus?

When you fit a probe into the machine’s shank/holder it is not necessary for the probe’s
stylus to run true to the spindle centre line. A small amount of run-out can be tolerated.
However, it is good practice to mechanically adjust the stylus so that it is true to the
virtual Y axis. This helps reduce the effects of cosine errors when measuring different
sizes.

Calibrating the probe and stylus ensures that run-out is automatically accounted for.
Without calibration, run-out will lead to inaccurate results.

It is important that you calibrate the stylus of a Renishaw inspection probe in the following
circumstances:

 When a probe and stylus are to be used for the first time.

 When a new stylus is fitted to the probe.

 When it is suspected that the stylus has become distorted or that the probe has
crashed.

 At regular intervals to compensate for mechanical changes of your lathe.

Three different operations are used to calibrate a stylus. They are:

 Calibrating single-sided.

 Calibrating double-sided.

 Calibrating the probe length.

Single-sided calibration
Single-sided calibration determines the error value for the stylus ball in relation to a
known surface. This value is stored in the tool wear offset and is used automatically in the
measuring cycles.

NOTE: Only one edge of the stylus is calibrated. Therefore, all subsequent measuring
cycles must use only this calibrated edge.

Publication No. H-2000-6021

 Calibrating the probe 5-3

Double-sided calibration
Double-sided calibration determines the stylus offset and the radius of the stylus ball. The
offset is stored in the tool wear offset while the radius is stored in a macro variable. Both
values are used automatically in the measuring cycles.

NOTE: Both edges of the stylus are calibrated. Therefore, measuring cycles that use
both sides of the stylus can be used.

Calibrating the probe length

Calibrating a probe on a known reference surface determines the length of the probe,
based on the electronic trigger point. The stored value for length is different from the
physical length of the probe assembly.

Additionally, the operation can automatically compensate for machine and fixture height
errors by adjusting the length value of the probe that is stored.

Calibration cycles
Eight calibration cycles are provided with the Inspection software. Four are for calibrating
a probe positioned vertically and four are for calibrating a probe positioned horizontally.
They may be used in conjunction with one another for complete calibration of the probe.
The purpose of each macro is summarised below.

Macros O9601 and O9801 Used to establish the length of the probe in the tool
shank.

Macros O9602 and O9802 Used to establish the stylus offset (for double-sided
calibration only).

Macros O9603 and O9803 Used to establish the radius values of the stylus ball (for
double-sided calibration only).

Macros O9604 and O9804 Used to establish the error value of the stylus ball (for
single-sided calibration only).

For complete calibration of a probe system, use the macros as follows:

 For double-sided calibration of a vertically mounted probe, use macros O9601,

O9602 and O9603.

 For double-sided calibration of a horizontally-mounted probe, use macros O9801,

O9802 and O9803.

Publication No. H-2000-6021

5-4 Calibrating the probe

 For single-sided calibration of a vertically mounted probe, use macros O9601 and
O9604.

 For single-sided calibration of a horizontally-mounted probe, use macros O9801

and O9804.

The Renishaw calibration cycles are split into separate cycles for flexibility.

Publication No. H-2000-6021

 Calibrating the probe (probe vertical) 5-5

Calibrating the probe length (probe vertical) – O9601

Tt
Tool offset

Xx
reference
size

Figure 5.1 Calibrating the probe length (probe vertical)

Description

The probe is positioned adjacent to an X-axis reference surface. When the calibration
cycle is completed the active tool offset is adjusted to the reference surface.

Application

An approximate tool offset is loaded. The probe is positioned adjacent to the reference
surface.

When the cycle is run, the surface is measured and the tool offset is reset to a new value.
The probe is then returned to the start position.

Format

G65 P9601 Xx Tt

Example: G65 P9601 X50. T20

Publication No. H-2000-6021

5-6 Calibrating the probe (probe vertical)

Compulsory inputs
Tt t= The active tool offset number.

Xx x= The size of the reference surface.

Outputs

The active tool offset is set.

Example: Probe length calibration

O0001

Proprietary G and M codes

T0101 Select the probe.

M?? Switch on the probe.

G65P9610X60.F3000 Protected positioning move.

G65P9601X50.T1 Calibrate in the X direction and update tool offset 1.

G65P9610X100. Protected positioning move.

M?? Switch off the probe.

Publication No. H-2000-6021

 Calibrating the probe (probe vertical) 5-7

Calibrating the stylus Z tool offset double-sided (probe

vertical) – O9602

A B

Figure 5.2 Calibrating the stylus Z tool offset

double-sided (probe vertical)

Description

Before the cycle is run, the probe is positioned either above a pre-machined web (A) or
inside a pre-machined groove (B). When the cycle is completed, the tool offset is set to
the centre of the stylus in the Z axis.

Application

Pre-machine either a web or a groove with a suitable tool so that the exact centre of the
feature is known. Position the probe to the centre of the web or groove.

When the cycle is run, two measuring moves are made to determine the Z offset of the
stylus. The probe is then returned to the start position.

Format

G65 P9602 Zz Tt [ Rr Xx ]
where [ ] denote optional inputs.

Example: G65 P9602 Z50.005 T8. X50.

Compulsory inputs
Tt t= The tool offset number that will be updated.

Zz x= The nominal size of the feature.

Publication No. H-2000-6021

5-8 Calibrating the probe (probe vertical)

Optional input
Xx x= The absolute X-axis measuring position when calibrating on an external
feature. If this is omitted, a groove cycle is assumed.

For the Rr optional input, see Chapter 2, "Optional inputs".

Outputs

The Z tool offset will be updated to the centre of the stylus.

Example: Calibrating the stylus Z offset

Run a complete positioning and calibration program as follows.

Set the exact X and Z feature positions in a work offset (for example, using G54).

O0002

T0101 Select the probe.

M?? Switch on the probe.

G54 Select the work offset.

G65P9610Z-20.F3000 Protected positioning move over the groove.

G65P9610X20. Protected positioning move into the groove.

G65P9602Z50.T1 Calibrate in a 50 mm (1.97 in) groove and update tool offset 1.

G65P9610X100. Protected positioning move retract to 100 mm (3.94 in).

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

 Calibrating the probe (probe vertical) 5-9

Calibrating the stylus ball radius double-sided (probe vertical) –

O9603

A B

Figure 5.3 Calibrating the stylus ball radius

double-sided (probe vertical)

Description

Before the cycle is run, the probe is positioned either above a pre-machined web (A) or
inside a pre-machined groove (B). When the cycle is completed, the radius values of the
stylus ball are stored.

Application

The probe to be calibrated is positioned either above the web or inside the groove of
known size. The position of the web or groove is not critical.

When the cycle is run, two moves are made to determine the radius values of the stylus
ball. The probe is then returned to the start position.

Format

G65 P9603 Zz [ Rr Xx ]
where [ ] denote optional inputs.

Example: G65 P9603 Z50.005 X50.

Compulsory input
Zz z= The nominal size of the reference web or groove.

Publication No. H-2000-6021

5-10 Calibrating the probe (probe vertical)

Optional input
Xx x= The absolute X-axis measuring position when calibrating on an external
feature. If this is omitted, a groove cycle is assumed.

For the Rr optional input, see Chapter 2, "Optional inputs".

Outputs

The following data will be stored:

#503 Stylus ball radius in Z.

NOTE: The actual variable is dependent on #112 that is set in O9724.

Example: Calibrating the radius of a stylus ball

Run a complete positioning and calibration program as follows.

Set the approximate X and Z feature positions in a work offset (for example, using G54).

O0004

T0101 Select the probe.

G54 Select the work offset.

M?? Switch on the probe.

G65P9610Z-20.F3000 Protected positioning move over the groove.

G65P9610X20. Protected positioning move into the groove.

G65P9603Z15.001 Calibrate in a 15.001 mm (0.5905 in) groove.

G65P9610X100. Protected positioning move retract to 100 mm (3.94 in).

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

 Calibrating the probe (probe vertical) 5-11

Calibrating the stylus single-sided (probe vertical) – O9604

NOTE: When this method is used for calibrating a stylus, only the calibrated edge of the
stylus must be used in subsequent measuring cycles.

OR
A B

Figure 5.4 Calibrating the stylus single-sided (probe vertical)

Description

Before the cycle is run, the probe is positioned adjacent to a Z axis reference surface.
When the cycle is completed, the active probe tool offset is adjusted to the reference
surface.

Application

An approximate tool offset is loaded. The probe is positioned adjacent to the reference
surface.

When the cycle is run, the surface is measured and the tool offset is reset to a new value.
The probe is then returned to the start position.

Format

G65 P9604 Zz Tt

Example: G65 P9604 Z0. T1.

Compulsory inputs
Tt t= The active tool offset number.

Zz z= The position of the reference surface.

Publication No. H-2000-6021

5-12 Calibrating the probe (probe vertical)

Outputs

The Z tool offset will be updated to the edge of the stylus.

Example: Calibrating a stylus edge

Run a complete positioning and calibration program as follows.

Set the exact X and Z feature positions in a work offset (for example, using G54).

O0002

T0101 Select the probe.

M?? Switch on the probe.

G54 Select the work offset.

G65P9610Z10.F3000 Protected positioning move.

G65P9610X20. Protected positioning move.

G65P9604Z0.T1 Calibrate in the Z direction and update tool offset 1.

G65P9610X100. Protected positioning move retract to 100 mm (3.94 in).

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

 Calibrating the probe (probe horizontal) 5-13

Calibrating the probe length (probe horizontal) – O9801

Tt tool offset

Zz reference height

Figure 5.5 Calibrating the probe length

(probe horizontal)

Description

The probe is positioned adjacent to a Z-axis reference surface for calibration. When the
cycle is completed, the active probe tool offset is adjusted to the reference surface.

Application

An approximate tool offset is loaded. The probe should be positioned adjacent to the
reference surface.

When the cycle is run, the surface is measured and the tool offset is reset to a new value.
The probe is then returned to the start position.

Format

G65 P9801 Zz Tt

Example: G65 P9801 Z–10. T20

Compulsory inputs
Tt t= The active tool offset number.

Zz z= The position of the reference surface.

Publication No. H-2000-6021

5-14 Calibrating the probe (probe horizontal)

Outputs

The active tool offset is set.

Example: Probe length calibration

O0001

T0101 Select the probe.

G54 Select the work offset.

M?? Switch on the probe.

G65P9810Z10.F3000 Protected positioning move.

G65P9801Z-10.T1 Calibrate in the Z direction and update tool offset 1.

G65P9810Z100. Protected positioning move.

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

 Calibrating the probe (probe horizontal) 5-15

Calibrating the stylus X tool offset double-sided (probe

horizontal) – O9802

Figure 5.6 Calibrating the stylus X tool offset

double-sided (probe horizontal)

Description

Before the cycle is run, the probe is positioned in front of the diameter (A) or inside the
bore (B). When this cycle is completed, the centre of the stylus is updated to the tool
offset.

Application

Pre-machine either a hole with a suitable boring bar or a diameter with a turning tool.
Position the probe as described above.

When the cycle is run, two measuring moves are made to determine the X offset of the
stylus. The probe is then returned to the start position.

Format

G65 P9802 Xx Tt [ Rr Zz ]
where [ ] denote optional inputs.

Example: G65 P9802 X50.005 T8. Z50.

Publication No. H-2000-6021

5-16 Calibrating the probe (probe horizontal)

Compulsory inputs
Tt t= The tool offset number that will be updated.

Xx x= The nominal size of the feature.

Optional input
Zz z= The absolute Z-axis measuring position when calibrating on an external
feature. If this is omitted, a bore cycle is assumed.

For the Rr optional input, see Chapter 2, "Optional inputs".

Outputs

The X tool offset will be updated to the centre of the stylus.

Example: Calibrating the stylus X offset

Run a complete positioning and calibration program as follows.

Set the exact X and Z feature positions in a work offset (for example, using G54).

O0002

T0101 Select the probe.

M?? Switch on the probe.

G65P9810X0.Z10.F3000 Protected positioning move over the hole.

G65P9810Z–5. Protected positioning move into the hole.

G65P9802X50.T1 Calibrate in a 50 mm (1.97 in) diameter bored hole and

update tool offset 1.

G65P9810Z100. Protected positioning move retract to 100 mm (3.94 in).

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

 Calibrating the probe (probe horizontal) 5-17

Calibrating the stylus ball radius double-sided (probe horizontal)

– O9803

Figure 5.7 Calibrating the stylus ball radius

double-sided (probe horizontal)

Description

Before the cycle is run, the probe is positioned either in front of the diameter (A) or inside
the bore (B). When the cycle is completed, the stylus centre is updated to the tool offset.

Application

Pre-machine either a hole with a suitable boring bar or a diameter with a turning tool.
Position the probe as described above.

When the cycle is run, two measuring moves are made to determine the X radius values
of the stylus ball. The probe is then returned to the start position.

Format

G65 P9803 Xx [ Rr Zz ]
where [ ] denote optional inputs.

Example: G65 P9803 X50.005 Z50.

Publication No. H-2000-6021

5-18 Calibrating the probe (probe horizontal)

Compulsory input
Xx x= The nominal size of the feature.

Optional input
Zz z= The absolute Z-axis measuring position when calibrating on an external
feature. If this is omitted, a ring gauge cycle is assumed.

For the Rr optional input, see Chapter 2, "Optional inputs".

Outputs

The following data will be stored:

#500 Stylus ball radius in X (XRAD)

NOTE: The actual variable is dependent on #111 that is set in O9724.

Example: Calibrating the radius of a stylus ball

Run a complete positioning and calibration program as follows.

Set the approximate X and Z feature positions in a work offset (for example, using G54).

O0004

T0101 Select the probe.

M?? Switch on the probe.

G65P9810X0.Z10.F3000 Protected positioning move over the hole.

G65P9810Z–5. Protected positioning move into the hole.

G65P9803X50.001 Calibrate in a 50.001 mm (1.9685 in) diameter ring gauge.

G65P9810Z100. Protected positioning move retract to 100 mm (3.94 in).

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

 Calibrating the probe (probe horizontal) 5-19

Calibrating the stylus single-sided (probe horizontal) – O9804

NOTE: When this method is used for calibrating a stylus, only the calibrated edge of the
stylus must be used in subsequent measuring cycles.

OR

Figure 5.8 Calibrating the stylus single-sided (probe horizontal)

Description

Before the cycle is run, the probe is positioned either above a diameter (A) or inside a
diameter (B). When the cycle is completed, the edge of the stylus is updated to the tool
offset.

Application

Pre-machine either a hole with a suitable boring bar or a diameter with a turning tool.
Position the probe as described above and run the cycle.

When the cycle is run, a measuring move is made to determine the X offset of the stylus.
The probe is then returned to the start position.

Format

G65 P9804 Xx Tt

Example: G65 P9804 X50.005 T8.

Compulsory inputs
Tt t= The active tool offset number.

Xx x= The nominal diameter of the feature.

Publication No. H-2000-6021

5-20 Calibrating the probe (probe horizontal)

Outputs

The X tool offset will be updated to the edge of the stylus.

Example: Single-sided stylus calibration

Run a complete positioning and calibration program as follows.

Set the exact X and Z feature positions in a work offset (for example, using G54).

O0002

T0808 Select the probe.

M?? Switch on the probe.

G65P9810X50.Z-6.F3000 Protected positioning move over the hole.

G65P9804X40.T8 Calibrate against a 40 mm (1.57 in) diameter and update

tool offset 8.

G65P9810Z100. Protected positioning move retract to 100 mm (3.94 in).

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

 Standard measuring cycles 6-1

Chapter 6

Standard measuring cycles

This chapter describes how to use the non-vector measuring cycles with vertically-
mounted and horizontally-mounted probes.

Contained in this chapter

XZ single surface measurement (probe vertical) – O9611 .............................................. 6-2

Web/pocket measurement (probe vertical) – O9612 ....................................................... 6-5

XZ single surface measurement (probe horizontal) – O9811 .......................................... 6-8

Web/pocket measurement (probe horizontal) – O9812 ................................................. 6-11

Publication No. H-2000-6021

6-2 Standard measuring cycles (probe vertical)

XZ single surface measurement (probe vertical) – O9611

Figure 6.1 Measurement of a single surface (probe vertical)

Description
This cycle measures a surface to establish the size or position.

Application
The probe, with its tool offset active, should be positioned adjacent to the surface. The
cycle measures the surface and returns to the start position.

There are two possibilities, as follows:

1. The surface can be treated as a size, where the tool offset is updated in conjunction
with the Tt and the Hh input.

2. The surface can be treated as a reference surface position, for the purpose of
adjusting a work offset using the Ss and Mm inputs.

Format
G65 P9611 Xx or Zz [ Cc Ee Ff Hh Ii Qq Ss Tt Uu Vv Ww ]
where [ ] denote optional inputs.

Example: G65 P9611 X50. C1. E90. F0.8 H0.2 I0.5 Q10. S1. T20. U.5 V.5 W2.

Compulsory inputs
Xx x= The size of the target surface.

or

Zz z= The position of the target surface.

Publication No. H-2000-6021

 Standard measuring cycles (probe vertical) 6-3

Optional inputs
Inputs Cc and Ii are used with the reference touch option. This option eliminates thermal
growth errors from within the probe results, helping to maintain measuring accuracy.

Cc c = 1. Takes the error from the reference diameter and stores it in #134.
c = 2. Takes the error stored in #134 and adds it to the results of the measured
diameter.

Ii i= This is the maximum tolerance used with the C input.

For other optional inputs, see Chapter 2, "Optional inputs".

C=1

C=2

Chuck

Figure 6.2 Reference touch option

Example: X and Z single surface measurement

1
7
5

6 4
2

Figure 6.3 Probe movements

Publication No. H-2000-6021

6-4 Standard measuring cycles (probe vertical)

T???? Select the probe.

M?? Switch on the probe.

1. G65P9610X50.Z10.F3000 Protected positioning move to the start position.

2. G65P9610X15. Protected positioning move.

3. G65P9611Z0.T2 Single surface measure.

4. G65P9610X80. Protected positioning move.

5. G65P9610Z–6. Protected positioning move.

6. G65P9611X40.T4 Single surface measure.

7. G65P9610X100. Protected positioning move.

M?? Switch off the probe.

continue

Tool offset 2 (Z wear) and tool offset 4 (X wear) will be updated.

Publication No. H-2000-6021

 Standard measuring cycles (probe vertical) 6-5

Web/pocket measurement (probe vertical) – O9612

NOTE: This cycle must not be used unless double-sided calibration has taken place.

Figure 6.4 Measurement of a web or pocket feature (probe vertical)

Description
This cycle measures a web or pocket feature. It uses two measuring moves along the
Z axis.

Application
Position the probe to the expected centre line of the feature and at a suitable position in
the X axis with the probe and probe offset active. Run the cycle with suitable inputs as
described.

Format
G65 P9612 Zz [ Ee Ff Hh Mm Qq Rr Ss Tt Uu Vv Ww ]
or
G65 P9612 Xx Zz [ Ee Ff Hh Mm Qq Rr Ss Tt Uu Vv Ww ]

where [ ] denote optional inputs.

Example: G65 P9612 X50. Z100. E91 F0.8 H0.2 M.2 Q10. R10. S1. T20. U.5 V.5 W2.

Publication No. H-2000-6021

6-6 Standard measuring cycles (probe vertical)

Compulsory inputs
Xx x= The absolute X-axis position when measuring a web feature. If this is
omitted, a pocket cycle is assumed.

Zz z= The nominal size of the feature when measured in the Z axis.

Optional inputs
See Chapter 2, "Optional inputs".

Outputs
See Chapter 3, "Variable outputs".

Example 1: Measuring a web

1
5
2

4 3

Figure 6.5 Probe movements

G54

T????? Select the probe.

M?? Switch on the probe.

1. G65P9610Z20.X60.F3000 Protected positioning move.

2. G65P9610Z0. Protected positioning move.

3. and 4. G65P9612X40.Z10.S2 Measure a 10.0 mm (1.968 in) wide web.

Publication No. H-2000-6021

 Standard measuring cycles (probe vertical) 6-7

5. G65P9610X100. Protected positioning move.

M?? Switch off the probe.

continue

The centre line of the feature in the X axis is stored in the work offset 02 (G55).

Example 2: Measuring a pocket (referred datum)

5 1

4
2

Figure 6.6 Probe movements

G54

T????? Select the probe.

M?? Switch on the probe.

1. G65P9610X100.Z20.F3000 Protected positioning move.

2. G65P9610Z–20. Protected positioning move.

3. G65P9610X40. Protected positioning move.

4. G65P9612Z10.S2 Measure a 10.0 mm (1.181 in) wide pocket.

5. G65P9610X100. Protected positioning move.

M?? Switch off the probe.

continue

The error of the centre line is referred to the datum point Z0 and the revised Z0 position is
set in work offset 02 (G55).

Publication No. H-2000-6021

6-8 Standard measuring cycles (probe horizontal)

XZ single surface measurement (probe horizontal) – O9811

Figure 6.7 Measurement of a single surface (probe horizontal)

Description
This cycle measures a surface to establish the size or position.

Application
The probe, with its tool offset active, should be positioned adjacent to the surface. The
cycle measures the surface and returns to the start position.

There are two possibilities, as follows:

1. The surface can be treated as a size, where the tool offset is updated in conjunction
with the Tt and the Hh input.

2. The surface can be treated as a reference surface position, for the purpose of
adjusting a work offset using the Ss and Mm inputs.

Format
G65 P9811 Xx or Zz [ Cc Ee Ff Hh Ii Qq Ss Tt Uu Vv Ww ]
where [ ] denote optional inputs.

Example: G65 P9811 X50. C1. E90 F0.8 H0.2 I0.5 Q10. S1. T20. U.5 V.5 W2.

Compulsory inputs
Xx x= The size of the target surface.

or

Zz z= The position of the target surface.

Publication No. H-2000-6021

 Standard measuring cycles (probe horizontal) 6-9

Optional inputs
Inputs Cc and Ii are used with the reference touch option. This option eliminates thermal
growth errors from within the probe results, helping to maintain measuring accuracy.

Cc c = 1. Takes the error from the reference diameter and stores it in #134.
c = 2. Takes the error stored in #134 and adds it to the results of the measured
diameter.

Ii i= This is the maximum tolerance used with the C input.

For other optional inputs, see Chapter 2, "Optional inputs".

C=1

C=2
Chuck

Figure 6.8 Reference touch option

Example: X and Z single surface measurement

1

7
5

6 4
2

Figure 6.9 Probe movements

G54

T????? Select the probe.

Publication No. H-2000-6021

6-10 Standard measuring cycles (probe horizontal)

M?? Switch on the probe.

1. G65P9810Z10.F3000 Protected positioning move.

2. G65P9810X20. Protected positioning move to the start position.

3. G65P9811Z0.T2 Single surface measure.

4. G65P9810X80. Protected positioning move.

5. G65P9810Z–20. Protected positioning move.

6. G65P9811X60.T4 Single surface measure.

7. G65P9810X100. Protected positioning move.

M?? Switch off the probe.

continue

Tool offset 2 (Z wear) and tool offset 4 (X wear) will be updated.

Publication No. H-2000-6021

 Standard measuring cycles (probe horizontal) 6-11

Web/pocket measurement (probe horizontal) – O9812

NOTE: This cycle must not be used unless double-sided calibration has taken place.

Figure 6.10 Measurement of a web or pocket feature (probe horizontal)

Description
This cycle measures a web or pocket feature. It uses two measuring moves along the X axis.

Application
Position the probe to the expected centre line of the feature and at a suitable position in
the Z axis with the probe and probe offset active. Run the cycle with suitable inputs as
described.

Format
G65 P9812 Xx [ Ee Ff Hh Mm Qq Rr Ss Tt Uu Vv Ww ]
or
G65 P9812 Xx Zz [ Ee Ff Hh Mm Qq Rr Ss Tt Uu Vv Ww ]
where [ ] denote optional inputs.

Example: G65 P9812 X50. Z100. E92 F0.8 H0.2 M.2 Q10. R10. S1. T20. U.5 V.5 W2.

Publication No. H-2000-6021

6-12 Standard measuring cycles (probe horizontal)

Compulsory inputs
Xx x= The nominal size of the feature.

or

Zz z= The absolute Z-axis position when measuring a web feature. If this is

omitted, a pocket cycle is assumed.

Optional inputs
See Chapter 2, "Optional inputs".

Outputs
See Chapter 3, "Variable outputs".

Example 1: Measuring a web

3
4

2
1

7
6
Figure 6.11 Probe movements

G54

T????? Select the probe.

M?? Switch on the probe.

G65P9810.Z10.F3000 Protected positioning move.

1. G65P9810X0. Protected positioning move.

2 to 7. G65P9812X50.Z–10.S2 Measure a 50.0 mm (1.968 in) wide web.

G65P9810Z10. Protected positioning move.

Publication No. H-2000-6021

 Standard measuring cycles (probe horizontal) 6-13

M?? Switch off the probe.

continue

The centre line of the feature in the X axis is stored in work offset 02 (G55).

Example 2: Measuring a pocket

2 1

Figure 6.12 Probe movements

T????? Select the probe.

M?? Switch on the probe.

1. G65P9810Z10.F3000 Protected positioning move.

2. G65P9810Z-10. Protected positioning move.

3. G65P9812X30.S2 Measure a 30.0 mm (1.181 in) wide pocket.

G65P9810Z10. Protected positioning move.

M?? Switch off the probe.

continue

The centre line of the feature in the X axis is stored in work offset 02 (G55).

Publication No. H-2000-6021

6-14 Standard measuring cycles (probe horizontal)

This page is intentionally left blank.

Publication No. H-2000-6021

 Additional cycles 7-1

Chapter 7

Additional cycles

The Inspection software contains four macro cycles that cannot be described under the
headings used in previous chapters (see chapters 4 to 6 inclusive). This chapter
describes how to use these cycles.

Contained in this chapter

Storing multi-stylus data (probe vertical) – O9630 ........................................................... 7-2

Loading multi-stylus data (probe vertical) – O9631.......................................................... 7-4

Storing multi-stylus data (probe horizontal) – O9830 ....................................................... 7-6

Loading multi-stylus data (probe horizontal) – O9831 ..................................................... 7-8

Publication No. H-2000-6021

7-2 Additional cycles (probe vertical)

Storing multi-stylus data (probe vertical) – O9630

Probe 1 Probe 2

K1 K2
Calibration data Calibration data

Figure 7.1 Storing multi-stylus data (probe vertical)

Description
The macro is used to store the stylus calibration data that is established during the
calibration cycles. The data is stored in a spare set of macro variables.

Stored data for each probe can be recalled using macro O9631.

Application
Calibrate the stylus using macros O9602 and O9603. Run macro O9630 to store the
calibration data #503. The values are recalled when macro O9631 is run.

NOTE: All # numbers shown are with the base number set to 503 in O9524.

Format
G65 P9630 Kk

Example: G65 P9630 K1.

Publication No. H-2000-6021

 Additional cycles (probe vertical) 7-3

Compulsory input
Kk k= This is the multi-stylus probe number that is used for storing calibration
data.
The active calibration data is stored in the macro variables shown in the
following table. The actual variables used are dependent on the #112
setting in O9524.

Active data K1 K2

Ball radius Z #503 #504 #505

NOTE: Spare macro variable locations, in which the calibration data can be stored, are
dependent on the machine options available and the variables that are already used by
your programs. These can be moved, depending on the #112 setting in O9524.

Example: Multi-stylus store K1

O0003

G54

M?? Switch on the probe.

G65P9610X5.F3000 Protected positioning move for X.

G65P9603Z50.001 Calibrate in a reference feature (a ring gauge).

G65P9630K1. Store calibration values for multi-stylus K1.

G65P9610X100. Protected positioning move.

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

7-4 Additional cycles (probe vertical)

Loading multi-stylus data (probe vertical) – O9631

Probe 1 Probe 2

K1 K2
Calibration data Calibration data

Figure 7.2 Loading multi-stylus data (probe vertical)

Description
This macro is used (in conjunction with O9630) to load stored calibration data for a
specific probe/stylus configuration into the active calibration variable range. It must be run
before using the probe and stylus.

Application
The program must be run immediately before a measuring cycle to select the correct
probe calibration data. The Kk input determines the data that is to be loaded.

NOTE: All # numbers shown are with the base number set to 503 in O9524.

Format
G65 P9631 Kk

Example: G65 P9631 K1.

Publication No. H-2000-6021

 Additional cycles (probe vertical) 7-5

Compulsory input
Kk k= This is the multi-stylus probe number that is used for loading stored data.
For a specific probe/stylus configuration, the Kk input number must be
the same as that used when storing the data with O9630.
The active calibration data is stored in the macro variables shown in the
following table. The actual variables used are dependent on the #112
setting in O9524.

Active data K1 K2

Ball radius Z #503 #504 #505

NOTE: Spare macro variable locations, in which the calibration data can be stored, are
dependent on the machine options available and the variables that are already used by
your programs. These can be moved, depending on the #112 setting in O9524.

Example: Multi-stylus load K1

G54

M?? Switch on the probe.

G65P9610X10.F3000 Protected positioning move.

G65P9631K1. Load calibration values for multi-stylus K1.

G65P9612Z30.S2 Measure a 30.0 mm (1.181 in) diameter bore.

G65P9610X10. Protected positioning move.

G65P9610Z350. Protected positioning move.

M?? Switch off the probe.

continue

Publication No. H-2000-6021

7-6 Additional cycles (probe horizontal)

Storing multi-stylus data (probe horizontal) – O9830

Probe 1

K1
Calibration
data

Probe 2

K2
Calibration
data

Figure 7.3 Storing multi-stylus data (probe horizontal)

Description
This macro is used to store stylus calibration data that is established during the calibration
cycles. The data is stored in a spare set of macro variables.

Stored data for each probe can be recalled using macro O9831.

Application
Calibrate the stylus using macro O9802 and O9803. Run macro O9830 to store the
calibration data #500. The values are recalled when macro O9831 is run.

NOTE: All # numbers shown are with the base number set to 500 in O9724.

Format
G65 P9830 Kk

Example: G65 P9830 K1.

Compulsory input
Kk k= This is the multi-stylus probe number that is used for storing calibration
data.
The active calibration data is stored in the macro variables shown in the
following table. The actual variables used are dependent on the #111
setting in O9724.

Publication No. H-2000-6021

 Additional cycles (probe horizontal) 7-7

Active data K1 K2

Ball radius X #500 #501 #502

NOTE: Spare macro variable locations, in which the calibration data can be stored, are
dependent on the machine options available and the variables that are already used by
your programs. These can be moved, depending on the #111 setting in O9724.

Example: Multi-stylus store K1

O0003

G54

M?? Switch on the probe.

G65P9810Z-5.F3000 Protected positioning move for Z.

G65P9803X50.001 Calibrate in a reference feature (a ring gauge).

G65P9830K1. Store calibration values for multi-stylus K1.

G65P9810Z100. Protected positioning move.

M?? Switch off the probe.

M30 End of the program.

Publication No. H-2000-6021

7-8 Additional cycles (probe horizontal)

Loading multi-stylus data (probe horizontal) – O9831

Probe 1

K1
Calibration
data

Probe 2

K2
Calibration
data

Figure 7.4 Loading multi-stylus data (probe horizontal)

Description
This macro is used (in conjunction with O9830) to load stored calibration data for a
specific probe/stylus configuration into the active calibration variable range. It must be run
before using the probe and stylus.

Application
The program must be run immediately before any measuring cycle to select the correct
probe calibration data. The Kk input determines the data that is to be loaded.

NOTE: All # numbers shown are with the base number set to 500 in O9724.

Format
G65 P9831 Kk

Example: G65 P9831 K1.

Compulsory input
Kk k= This is the multi-stylus probe number that is used for loading stored data.
For a specific probe/stylus configuration, the Kk input number must be
the same as that used when storing the data with O9830.
The active calibration data is stored in the macro variables shown in the
following table. The actual variables used are dependent on the #111
setting in O9724.

Publication No. H-2000-6021

 Additional cycles (probe horizontal) 7-9

Active data K1 K2

Ball radius X #500 #501 #502

NOTE: Spare macro variable locations, in which the calibration data can be stored, are
dependent on the machine options available and the variables that are already used by
your programs. These can be moved, depending on the #111 setting in O9724.

Example: Multi-stylus load K1

G54

M?? Switch on the probe.

G65P9810Z–10.F3000 Protected positioning move.

G65P9831K1. Load calibration values for multi-stylus K1.

G65P9812X30.S2 Measure a 30.0 mm (1.181 in) diameter bore.

G65P9810Z10. Protected positioning move.

G65P9810X350. Protected positioning move.

M?? Switch off the probe.

Publication No. H-2000-6021

7-10 Additional cycles (probe horizontal)

This page is intentionally left blank

Publication No. H-2000-6021

 C-axis cycles 8-1

Chapter 8

C-axis cycles

This chapter describes how to use the two C-axis macros that are supplied as part of the
Inspection software.

Contained in this chapter

C-axis find (probe vertical) – O9650 ................................................................................ 8-2

C-axis find (probe horizontal) – O9850 ............................................................................ 8-4

Publication No. H-2000-6021

8-2 C-axis cycles (probe vertical)

C-axis find (probe vertical) – O9650

Figure 8.1 C-axis find (probe vertical)

Description
This cycle will take two readings by moving the C axis. External features can also be
measured by moving the X axis. The results can be used to update a work shift.

Application
The stylus must be programmed to a start position that is either above an external feature
or inside an internal feature. The C axis must be engaged before calling up the cycle.

The inclusion of an Xx input indicates that an external feature is to be measured.

Format
G65 P9650 Dd [ Xx Qq Rr Hh Ss ]
where [ ] denote optional inputs.

Example: G65 P9650 D20. X10. Q10. R10. H0.2 S1.

Compulsory input
Dd d= The linear width of the feature.

Optional inputs
Hh h= Half the total positional tolerance.

Qq q= The amount of scan past the nominal surface position and the clearance
for external features.
Default: 5 mm.

Publication No. H-2000-6021

 C-axis cycles (probe vertical) 8-3

Rr r= The clearance move amount in C for an external feature only (angle

value).
Default: 5 mm plus the ball radius converted into an angle.

Xx x= The absolute X position at which a reading is taken when measuring a

external feature.

For the Ss optional input, see Chapter 2, “Optional inputs”.

Example: Bore
Bore size = 20.0

X position = X60.0

Z position = Z–40.0

X100.0Z20.0C0 Move to the safe position.

G65P9610Z–40.0 Move over the bore.

G65P9610X60.0 Move into the bore.

G65P9650D20.0 Measure the bore.

G65P9610X100.0 Move out of the bore.

G65P9610Z20.0 Move to the start position.

Publication No. H-2000-6021

8-4 C-axis cycles (probe horizontal)

C-axis find (probe horizontal) – O9850

Figure 8.2 C-axis find (probe horizontal)

Description
This cycle will take two readings by moving the C axis. External features can also be
measured by moving the Z axis. The results can be used to update a work shift.

Application
The stylus must be programmed to a start position that is either above an external feature
or inside an internal feature. The C axis must be engaged before calling up the cycle.

The inclusion of a Zz input indicates that an external feature is to be measured.

Format
G65 P9850 Dd [ Zz Qq Rr Hh Ss ]
where [ ] denote optional inputs.

Example: G65 P9850 D20. Z10. Q10. R10. H0.2 S1.

Compulsory input
Dd d= The linear width of the feature.

Optional inputs
Hh h= Half the total positional tolerance.

Qq q= The amount of scan past the nominal surface position and the clearance
for external features.
Default: 10°.

Publication No. H-2000-6021

 C-axis cycles (probe horizontal) 8-5

Rr r= The clearance move amount in C for an external feature only (angle

value).
Default: 5 mm plus the ball radius converted into an angle.

Zz z= The absolute Z position at which a reading is taken when measuring an

external feature.

For the Ss optional input, see Chapter 2, “Optional inputs”.

Example: Bore
Bore size = 20.0

X position = X60.0

Z position = Z–40.0

X100.0Z20.0C0 Move to the safe position.

G65P9810X60.0 Move over the bore.

G65P9810Z–40.0 Move into the bore.

G65P9850D20.0 Measure the bore.

G65P9810Z20.0 Move out of the bore.

Publication No. H-2000-6021

8-6 C-axis cycles (probe horizontal)

This page is intentionally left blank

Publication No. H-2000-6021

 Alarms and error messages 9-1

Chapter 9

Alarms and error messages

When an error occurs during use of the Inspection software, an alarm number or
message is generated. This is displayed on the screen of the controller.

This chapter describes the meaning and likely cause of each alarm message that may be
displayed. It then describes typical actions you should take to clear the fault.

Contained in this chapter

General alarms ................................................................................................................ 9-2

Publication No. H-2000-6021

9-2 Alarms and error messages

General alarms
Format:

#148 flag
3006= 1 (OUT OF TOLERANCE) Updates the offset if the cycle 1
1 (OUT OF POSITION) start button is pressed to 2
1 DIA OFFSET TOO LARGE continue. 5

1 (UPPER TOL EXCEEDED) No offset update if the cycle 3

start button is pressed to
continue.
Action: Press cycle start to continue.

Format: #3000 = 91 (MESSAGE)

(FORMAT ERROR)
(K INPUT MISSING)
(T INPUT MISSING)
(X INPUT MISSING)
(Y INPUT MISSING)
(Z INPUT MISSING)
(SH INPUT MIXED)
(ST INPUT MIXED)
(TM INPUT MIXED)
(XZ INPUT MIXED)
(K INPUT OUT OF RANGE)
Action: Edit the program and start again from a safe start position.
This is a reset condition.

Format: #3000 = 86 (PATH OBSTRUCTED)

Cause: The probe has made contact with an obstruction. This alarm occurs only
during a protected positioning cycle.
Action: Edit the program. Clear the obstruction and start again from a safe position.
This is a reset condition.

Format: #3000 = 88 (NO FEEDRATE)

Cause: This alarm occurs only during a protected positioning cycle.
Action: Edit the program. Insert the F___ code input and start again from a safe
position.
This is a reset condition.

Publication No. H-2000-6021

 Alarms and error messages 9-3

Format: #3000 = 92 (PROBE OPEN)

Cause: This alarm occurs if the probe is already triggered before a move.
The stylus may be in contact with a surface or the probe has failed to reseat.
This could be due to swarf trapped around the probe eyelid.
Action: Clear the fault and start again from a safe start position.
This is a reset condition.

Format: #3000 = 93 (PROBE FAIL)

Cause: This alarm occurs if the probe did not trigger during the move.
The surface was not found or the probe has failed.
Action: Edit the program and start again from a safe start position.
This is a reset condition.

Format: #3000 = 94 (C POSITION ERROR)

Cause: The positional error of the feature exceeds the tolerance value (H).
Action: Reload the component and start again from a safe start position.
This is a reset condition.

Format: #3000 = 95 (CHECK SETTINGS #120)

Cause: This alarm occurs if the settings in O9724 are set incorrectly.
Action: Edit the program O9724 with correct values.

Publication No. H-2000-6021

9-4 Alarms and error messages

This page is intentionally left blank

Publication No. H-2000-6021

 Settings, macros and variables 10-1

Chapter 10

Settings, macros and variables

Contained in this chapter

Customising the software............................................................................................... 10-2
Editing the settings macro (O9524 or O9724) ........................................................ 10-2
Setting #33 .............................................................................................................. 10-3
Variable base number setting (#111 and #112) ...................................................... 10-3
Alarm settings (#110) .............................................................................................. 10-3
Process alarms ....................................................................................................... 10-4

Work offset update tests ................................................................................................ 10-4

Use of macro variables .................................................................................................. 10-4

Local variables ........................................................................................................ 10-4
Common variables .................................................................................................. 10-5
Common retained variables .................................................................................... 10-6

Publication No. H-2000-6021

10-2 Settings, macros and variables

Customising the software

Editing the settings macro (O9524 or O9724)
A settings macro (O9524 or O9724) is called at the beginning of each top-level macro to
establish the necessary modal information. If the default values are not suitable, you will
need to change the values during installation by editing this macro.

The following options of macros O9524 and O9724 will need to be set:

 Tolerance alarms or flag only (FMS type application).

 Tool offset type.

 Variable base number.

The examples in this chapter are for general guidance only. Note that the exact
programming format may not suit either your machine set or the recommended method
as specified by your machine builder.

#33 = 1 (SET TO 1/2/3/4/5) See “Setting #33” later in this chapter.

#120 = 1 If less than 64, tool offset = 1.

If greater than 64, tool offset = 2.

#111 = 500 See "Variable base number setting (#111 and

#112)" later in this chapter.

#112 = 503 See "Variable base number setting (#111 and

#112)" later in this chapter.

#119 = 5000 (FAST FEED MM) The fast feedrate of the cycles can be adjusted by
#119 = 200 (FAST FEED INCH) this variable to suit the machine characteristics
and should be optimised.

NOTES:

1. The Z-axis P9726 basic move macro fast feedrate is at the #119×.6 value
(3000 mm/min as standard).

2. All Z-axis positioning moves are also at the #119×.6 value (3000 mm/min as
standard).

3. All X-axis positioning moves are at the #119 value (5000 mm/min as standard).

#123 = .05 (POSITION ZONE MM) This is the zone at either the start or end of the
block in which the cycle is aborted with either a
PROBE OPEN or PROBE FAIL message.

Publication No. H-2000-6021

 Settings, macros and variables 10-3

Setting #33
It has been found that machine configurations can vary between different machine tool
builders. This means that a modification to #33 may be necessary. To establish whether
#33 needs modifying, carry out the following procedure:

1. Load approximate values into the probe tool offset. This includes entering small
values (0.5 mm [0.019 in]) into the wear columns.

2. Set a work offset to a convenient position.

3. Send the machine to a position that is clear of any obstruction; for example, the
reference point is ideal.

4. Switch on the probe.

5. Run a protected positioning cycle and move to a position at which no collision will
occur.

6. If the cycle completes with no alarm, no edits are required to #33.

If the PROTECTED POSITIONING alarm is issued, edit #33 to the next option then
repeat the procedure.

7. When no alarm occurs, #33 is set correctly.

Variable base number setting (#111 and #112)

The base number defines the first variable in the set of variables used for setting and
calibration data. The default values are 500 (#500) and 503 (#503). A default value may
be changed by editing the settings macro (O9524 or O9724). The base number edit is
found near the top of this macro:

#111 = 500 (EDIT HORIZ BASE NO.)

#112 = 503 (EDIT VERT BASE NO.)

See “Use of macro variables” later in this chapter for a full list of the variables affected.
Before editing, check the availability of the variables.

Alarm settings (#110)

Using #110, the software can be set to operate in either of the following modes:

 Stop the machine at the end of the measuring cycle with an alarm message and set
the alarm flag #148.

 Set the alarm flag #148 only, allowing the process to continue.

Publication No. H-2000-6021

10-4 Settings, macros and variables

#110 = 0 If one of the conditions ( * ) listed below in “Process

alarms” occurs, the cycle stops with an alarm
message and flag #148 is set as appropriate.
Otherwise flag #148 = 0 is set and the cycle
continues.

#110 = 1 If one of the conditions ( * ) listed below in “Process

alarms” occurs, flag #148 is set as appropriate but
the cycle does not stop. Otherwise flag #148 = 0 is
set and the cycle continues.

Process alarms
* No alarm #148 = 0

* Out of tolerance #148 = 1

* Out of position #148 = 2

* Upper tolerance exceeded #148 = 3

* Diameter offset too large #148 = 5

NOTE: If it is necessary to switch this option on and off during the program, then the
following line in macro O9524 or O9724 may be deleted during installation. #110 can then
be programmed.
#110 = 0(SELECT ALARM METHOD).

Work offset update tests

It has been found that machines can be set for either positive or negative work offset
updating. This means that a modification to the software may be necessary. Edit the
following line at the start of macro O9732 and/or O9532.

#30=1(±AXIS UPDATE) Example +1 or –1.

Use of macro variables

Local variables
#1 to #32 These are used within each macro as necessary for calculation etc.

Publication No. H-2000-6021

 Settings, macros and variables 10-5

Common variables
#100 to #105 Not used by this software package.

#106 Basic move control factor (see Figure 10.1). This is used to control the
back-off distance in the basic move before the final gauge move. It
should be fine-tuned on installation to suit the machine.
A default value of 0.5 is installed by the software. The actual factor
should normally be between 0 and 1.0. Reduce the value to reduce the
back-off distance.

(a) (c)

(b)

X
X
#106
(Basic move
control factor)
x

1 2 3

Move 1: Fast feed to find the surface. a = Fast feed.

Move 2: Recover off the surface. b = Gauge feed
(30 mm/min).
Move 3: Gauge feed 30 mm/min (1.2 in/min). c = Return.

Figure 10.1 Basic move control factor

#108 Radius or diameter programming.

#109 Target position for C-axis cycles.

#110 Flag or alarm selection (see “Editing the settings macro (O9524 or
O9724)” earlier in this chapter).

#111 Variable base number (probe horizontal).

#112 Variable base number (probe vertical).

#113 Transfer location for C-axis cycles.

#114 Active tool length X axis.

#116 Active tool length Z axis.

#117 Modal feedrate value used in the protected positioning macros (O9610
and O9810).

#118 RADIUS TOO LARGE flag macros O9612 and O9812.

Publication No. H-2000-6021

10-6 Settings, macros and variables

#119 Fast feedrate value. This is set in macro O9524 or O9724 at

5000 mm/min (200 in/min) default value.

#120 Setting variable used in macros O9524 and O9724.

#121 Print option. The 6-digit component number is incremented by 1 with

each heading program. To reset, state #121 = 0.

#122 The 4-digit feature number is incremented by 1 with each print macro
call program. To reset, state #122 = 0.

#123 Start and end of block position zone normal setting 0.05 mm
(0.002 in). If the skip position is within this zone, the cycle aborts with
either a PROBE OPEN or PROBE FAIL alarm.

#124 Stored X skip position at the end of the basic move macro O9726.

#125 Stored skip for C-axis cycles.

#126 Stored Z skip position at the end of the basic move macro O9726.

#127 X average skip position at the end of the X diameter move macro
O9721.

#129 Inch/metric multiplier (0.04/1.0).

#130 to #133 Not used by this software.

#134 Error store when using the C1 input macros O9611 and O9811.

#135 to #149 See Chapter 3, "Variable outputs".

#150 onwards Not used by this software.

Common retained variables

The actual common retained variables that are used are determined by the values set in #111
and #112 in the settings macro (O9524 or O9724). Default values are 500 for #111 and 503 for
#112 (see “Variable base number setting (#111 and #112)” earlier in this chapter).

#500 [111+0] (XRAD) X calibration radius (probe horizontal).

#501 [111+1] Multi-stylus storage K1 (probe horizontal).

#502 [111+2] Multi-stylus storage K2 (probe horizontal).

#503 [112+0] (ZRAD) Z calibration radius (probe vertical).

#504 [112+1] Multi-stylus storage K1 (probe vertical).

#505 [112+2] Multi-stylus storage K2 (probe vertical).

Publication No. H-2000-6021

 General information 11-1

Chapter 11

General information

Contained in this chapter

Tolerances ..................................................................................................................... 11-2

Experience values Ee .................................................................................................... 11-3

Reason for using this option ................................................................................... 11-3

Printing a macro output – an example ........................................................................... 11-3

Publication No. H-2000-6021

11-2 General information

Tolerances
Uu, Hh and Vv apply to size and tool offset updates only.

Uu
c d e
Hh

a
Vv b

a = Nominal size.

b = Null band. This is the tolerance zone where no tool offset adjustment occurs.

c = Area where the Ff input is effective in percentage feedback. F (0 to 1) gives 0% to 100%

feedback to the tool offset.

d = OUT OF TOLERANCE alarm occurs. The tolerance value that applies to the size of the
feature is defined by input Hh.

e = Uu upper tolerance. If this value is exceeded, no tool offset or work offset is updated
and the cycle stops with an alarm. This tolerance applies to both size and position
where applicable.

Figure 11.1 Size and tool offset update tolerances

Publication No. H-2000-6021

 General information 11-3

Experience values Ee
The measured size can be adjusted by an amount stored in a spare tool offset.

Example:

Measure a 40 mm diameter and update tool offset 20.

G65 P9812 D40. T20 E21 An experience value stored in tool offset 21 will be
added to the measured size.

Reason for using this option

Component clamping forces in some applications can influence the measured size.
Therefore, an adjustment value to relate measurement to a traceable standard, such as a
co-ordinate measuring machine, is desirable. Thermal effects can also be compensated
by this means.

Printing a macro output – an example

--------------------------------------------------------------------------
COMPONENT NO 31 FEATURE NO 1
--------------------------------------------------------------------------

POSN R79.0569 ACTUAL 79.0012 TOL TP 0.2000 DEV -0.0557

POSN X-45.0000 ACTUAL -45.1525 TOL TP 0.2000 DEV -0.1525
POSN Y-65.0000 ACTUAL -64.8263 TOL TP 0.2000 DEV 0.1737

+++++OUT OF POS+++++ ERROR TP 0.1311 RADIAL

ANG -124.6952 ACTUAL -124.8578 DEV -0.1626

---------------------------------------------------------------------------
COMPONENT NO 31 FEATURE NO 2
---------------------------------------------------------------------------

SIZE D71.0000 ACTUAL 71.9072 TOL 0.1000 DEV 0.9072

+++++OUT OF TOL+++++ ERROR 0.8072

POSN X-135.0000 ACTUAL -135.3279 DEV -0.3279

POSN Y-65.0000 ACTUAL -63.8201 DEV 1.1799

Publication No. H-2000-6021

11-4 General information

This page is intentionally left blank.

Publication No. H-2000-6021

 Features, cycles and limitations A-1

Appendix A

Features, cycles and limitations

Contained in this appendix

Features of the Inspection software ................................................................................. A-2

Cycles .............................................................................................................................. A-2

Limitations ........................................................................................................................ A-2

Publication No. H-2000-6021

A-2 Features, cycles and limitations

Features of the Inspection software

 Protected positioning.

 Measurement of internal and external features to determine both size and position.
This includes:

 Obtaining a hard copy printout of feature data.

 Applying tolerances to both size and position.

 Additional features for feedback of errors include:

 Experience values can be applied to the measured size.

 Percentage feedback of the error can be applied.

 Null band zone for no tool offset update.

 Calibration of multiple styli.

 Software option to turn off the tolerance alarms and provide a flag-only alarm.
Suitable for FMS and unmanned applications.

 Built-in stylus collision and false trigger protection for all cycles.

 Diagnostic and format error checking routines for all cycles.

Cycles
 Protected positioning.

 Measurement:

 XZ single surface.

 Web/pocket.

 C-axis measurement.

 Multi-stylus calibration.

Limitations
 The probe cycles will not run if ‘mirror image’ is active.

 Consider macro variable availability.

Publication No. H-2000-6021

 Co-ordinate systems used on lathes B-1

Appendix B

Co-ordinate systems used on lathes

Contained in this chapter

Example 1 Tool offset geometry ..................................................................................... B-2

Example 2 Using either G54 to G59 or G50 to define the component zero ................... B-3
G54 to G59 method .................................................................................................. B-3
G50 method setting a program shift to the turret reference position ........................ B-4

Example 3 Using G10 to define the component zero ..................................................... B-5

Example 4 Using either G92 or G50 to define the component zero-to-tool tip
position ......................................................................................................................... B-6

!
CAUTION: While the examples described in this chapter are commonly used,
you must be aware that they might not be suitable for your machine. Care must be
taken if you change the method of co-ordinate system setting on your machine to one that
is described here.

Publication No. H-2000-6021

B-2 Co-ordinate systems used on lathes

Example 1 Tool offset geometry

Boring tool

Turning tool

Figure B.1 Example 1

a = the X geometry of the tool (2 × a for diameter type offsets)

b = the Z geometry of the tool

Publication No. H-2000-6021

 Co-ordinate systems used on lathes B-3

Example 2 Using either G54 to G59 or G50 to define the

component zero

Turret at
reference
X tool
offset

a
(diameter or
radius)

Component
zero Z
tool offset

Figure B.2 Example 2

G54 to G59 method

 Work offsets G54 to G59 can be collectively shifted by inputting data into the
external work shift co-ordinate system (offset 00 on work offset page).

 a and b may be minus values if the machine zero is at the turret home position.

O1234

G80G0

G28U0W0 Return to the reference position.

G55T0101X0Z10 Select G55 and tool 1, offset 1. The tool tip will move to
X0Z10 in the program co-ordinate system.

where the G55 X register = a and the Z register = b (see the description above).

Publication No. H-2000-6021

B-4 Co-ordinate systems used on lathes

G50 method setting a program shift to the turret reference

position
O1234

G80G0

G28U0W0 Return to the reference position.

G50X(a)Z(b) Set a program shift to the turret reference position.

T0101X0Z10 Select tool 1, offset 1. The tool tip will move to X0Z10 in the
program co-ordinate system.

where the G50 X = a (+ value to the turret reference) and Z = b (+ value to the turret
reference).

NOTE: For an alternative G50 method, see Example 4 later in this chapter.

Publication No. H-2000-6021

 Co-ordinate systems used on lathes B-5

Example 3 Using G10 to define the component zero

Turret at
reference

Machine zero (this position will

vary from machine to machine) Component
zero

Figure B.3 Example 3

G10 defines the distance and direction of the machine zero from the component zero.
Therefore in the example above:

a = zero (0).

b = minus value.

However, if the machine zero is at the turret home position then:

a = plus value.

b = plus value.

O1234
G80G0
G10P0X(a)Z(b)

The previous methods of co-ordinate system setting using either G54 to G59 or G10 can
use geometry type offsets (see Example 1). They are all methods of setting the
component zero relative to the turret face (that is, NOT the tool tip position).

These methods will allow the same tool offsets to be used in another job set-up. All that is
necessary is to redefine the new component zero.

Publication No. H-2000-6021

B-6 Co-ordinate systems used on lathes

Example 4 Using either G92 or G50 to define the component

zero-to-tool tip position

Turret at
reference

Component
zero a(Ø)
Z tool offset

Figure B.4 Example 4

G50 or G92

X = a (plus value).
Z = b (plus value).

! CAUTION: On some machines G92 may be a minus value.

O1234
G80G0
G28U0W0
G50X200.0Z100.0
T0101X30.0Z3.0 Select the tool and tool offset.
G28U0 W0T0100
G50X250.0Z75.0
T0202X0Z3.0
G28U0W0T0200

Publication No. H-2000-6021

 Co-ordinate systems used on lathes B-7

Tool offsets for a G50 (or G92) co-ordinate system will be small wear compensation
amounts and have no obvious relationship to the machine turret. When changing from job
to job, all tools will need their new G50 values reset, unlike the other methods described.
This means that tools will need resetting for each job.

Publication No. H-2000-6021

Renishaw plc T +44 (0)1453 524524
New Mills, Wotton-under-Edge, F +44 (0)1453 524901
Gloucestershire, GL12 8JR E uk@renishaw.com
United Kingdom www.renishaw.com

For worldwide contact details,

please visit our main web site at
www.renishaw.com/contact

*H-2000-6021-0E*